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This task shows you how to remove
a body from two parts. |
![](../icons_C2/common/aprereq.gif) |
Open the AssemblyRemove_Add.CATProduct
document. |
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1. |
Click the Remove icon . |
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2. |
Select Body.1 from MoldedPart as the body to be removed. |
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![](images/bt143.gif)
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3. |
The dialog box that appears
displays the names as well as the paths of the parts that may be affected
by the removal. |
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The assembly feature's name now
appears in the top left corner of the dialog box. If desired, you can edit
this name. |
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![](images/db067NLS.gif)
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The frame 'Affected parts' is exclusively
reserved for the parts you wish to use. For the purposes of our scenario, you
are going to remove material from Part2 and Part3.
Move these parts to the list 'Affected parts". To do so, select Part2 and click the
button. Repeat the operation for Part3. Alternatively, double-click each part.
The other three buttons lets you move the names of the parts from one
list to another too:
![](_themes/v5r5/ul1.gif) | moves
all selected parts to the list 'Affected parts' |
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![](_themes/v5r5/ul1.gif) | moves
all selected parts to the list 'Parts possibly affected' |
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![](_themes/v5r5/ul1.gif) | moves
the selected part to the list 'Parts possibly affected' |
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![](../icons_C2/common/iconblck.gif) |
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The Remove dialog box that has appeared, indicates the
part to be removed. |
![](images/db068NLS.gif) |
![](../icons_C2/common/iconblck.gif) |
4. |
Check the
option Highlight affected parts to clearly identify the parts affected by
the operation. |
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![](images/bt144.gif)
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5. |
Click OK
to confirm.
Material is removed from Part 2
and Part3. |
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6. |
To better visualize the result, put Part 5 and
Body.5 in no show mode. You can see the portion of material that has been
removed. |
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![](images/bt145.gif)
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A new entity 'Assembly Features' appears in the
specification tree. It contains the assembly removal referred to as
'Assembly Remove.1" and the name of affected parts.
Moreover, this feature has generated a remove feature in Part2 and a
remove feature in Part 3. An arrow
symbol identifies these removals in the tree, meaning that a
link exists between Assembly Remove.1and them.
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![](images/bt041NLS.gif) |
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Editing an Assembly Remove
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To edit an assembly remove operation, double-click
'Assembly Remove.X' entity. You can then modify the list of the parts
possibly affected by the removal. |
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Reusing Part Design Remove Features
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To increase your productivity, you can create
Assembly Remove Features from existing Part Design Remove features, or
more precisely by reusing the specifications you entered for designing
Part Design remove features. To do so, just proceed as follows: |
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1. |
Click the Remove icon . |
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2. |
Select the Part Design Remove
feature of interest. |
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3. |
Both the Remove Definition and the
Assembly Features Definition dialog boxes display. You then just need to
specify the parts of interest.
The assembly remove feature inherits the
specifications as displayed in the Part Design Remove Definition dialog
box. You can edit these specifications at any time. Editing an Assembly
feature created in this way does not affect the specifications used for
the Part Design feature.
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Reusing Assembly Design Remove Features
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The application also lets you reuse
Assembly Remove Features' specifications to accelerate the design process. In this
case, you just need to select the existing assembly remove feature, click the
Assembly remove icon and then select a face. Only the Assembly Features
Definition dialog box appears to let you determine the parts of interest. |
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