|
Sample: KwrPointConstructors
 |
point (x: Length, y: Length, z: Length):
Point
Creates a point from its three coordinates. Values or parameter names
can be used to pass the arguments.
Examples
Specifying values:
Open_body.1\Point.1 =
point(10mm,10mm,10mm)
Specifying parameter names:
Open_body.1\Point.4 =
point(0mm,L3,L1)
|
|
|
pointbetween(pt1: Point, pt2: Point, ratio: Real, orientation:
Boolean) : Point
Creates a point between another two points. If true is specified in the fourth argument,
the third parameter is the ratio of the distance pt1-new point to the pt1-pt2
distance. If false is specified in the fourth argument, the ratio expresses the distance
pt2-new point to the pt1-pt2 distance (to create a point at the middle between pt1 and pt2,
specify a ratio of 0.5).
Example
Open_body.1\Point.5 =
pointbetween(Open_body.1\Point.1, Open_body.1\Point.2, 0.6, true)
|
|
|
pointoncurve(crv:Curve, pt:Point, distance:Length, orientation:
Boolean) : Point
Creates a point on a curve. The point is to be created at a given curvilign distance
from a reference point specified in the second argument. The boolean specified in the fourth
argument allows you to reverse the direction in which the point is to be created. If the point
specified in the second argument is not on the curve, the projection of this point onto the
curve becomes the actual reference point.
Example
Open_body.1\Point.6 =
pointoncurve(Open_body.1\Spline.1, Open_body.1\Point.5, 5mm, true)
|
|
|
pointoncurveRatio(crv:Curve, pt:Point, ratio:Real, orientation:
Boolean) : Point
Creates a point on a curve. The location of the point to be created is determined by the
real which is specified in the third argument. This real is the ratio of the distance
[point to be created->reference point] to the distance [point to be created->curve
extremity]. The boolean specified in the fourth argument allows you to reverse the direction
in which the point is to be created. If the point specified in the second argument is not on
the curve, the projection of this point onto the curve becomes the actual reference point.
Example
Open_body.1\Point.7 =
pointoncurveRatio(Open_body.1\Spline.1,Open_body.1\Point.3, 0.4,true)
|
|
|
pointonplane(pln:Plane, pt:Point, dx:Length, dy:Length):
Point
Creates a point on plane. The location of the point to be created on the plane is
determined by the coordinates (H,V system) passed in the third and fourth arguments. These
values are specified with respect to the reference point passed in the second argument.
Example
Open_body.1\Point.8 =
pointonplane(Open_body.1\Plane.1,Open_body.1\Point.1, 10mm,10mm)
|
|
|
pointonsurface(sur:Surface, Pt:Point, Dir:Direction, dist:Length):
Point
Creates a point on surface. The location of the point to be created on the surface is
determined by its distance (fourth argument) to a reference point (second argument) along a
direction (third argument).
Example
Open_body.1\Point.9 =
pointonsurface(Open_body.1\Extrude.1,Open_body.1\Point.3,direction(Open_body.1\Line.1),10mm)
|
|
|
center(circle): Point
Creates a point from a circle. The circle can be of any type (sketch or GSM circle). The
point which is created is the circle center.
Example
Open_body.1\Point.10 =
circle(Open_body.1\Circle.1)
|
|
|
pointtangent(curve,direction): Point
Creates the tangency point between a curve and a direction.
Example
Open_body.1\Point.11 =
pointtangent( Open_body.1\Spline.1, direction(`yz plane`))
|
|
|
centerofgravity(Body): Point
Constructs the center of gravity of a solid (i.e. a PartBody type feature).
Example
Open_body.1\Point.12 =
centerofgravity(PartBody)
|
|
|
curvaturecenter(crv: Curve, pt: Point): Point
Constructs the curvature center of a curve for a given point.
Example
Open_body.1\Point.13 =
curvaturecenter(Open_body.1\Circle.1, Open_body.1\Point.6)
|
|
|
